Jump to content

Easiest way to turn on/off my laser for G0 moves then turn it back on for G1 draws using Cura???


MrMaint

Recommended Posts

Posted · Easiest way to turn on/off my laser for G0 moves then turn it back on for G1 draws using Cura???

I am using code to turn my laser on and off but need a way to get Cura to insert the code at the appropriate times.

I have been hand editing the g-code and inserting the code by hand which is getting tedious!

Each time I want the laser to turn off I put this code in:

G4 P0050 ; Pauses for 50 ms. This makes sure that the last move command executes before the laser turns off.

M104 S0 T2 ; Sets the #3 extruder heater output to off.

G0 Xnnn Ynnn ; General command for a non-printing move.

Each time I want the laser back on:

G4 P0050 ; pause

M104 S50 T2 ; Sets temp above threashold so it activates Laser to turn on.

G4 P0500 ; pauses a short 50ms so Laser can get fully turned on

Thanks!

Alex

.

  • Link to post
    Share on other sites

    Posted · Easiest way to turn on/off my laser for G0 moves then turn it back on for G1 draws using Cura???

    Hi,

    You could use a plugin in Cura, don't know if this worked, but an intern tried this a year ago:

    other option is to use regular expressions in a better text editor:

    find:

    G0 (.*)

    replace:

    yourcode

    G0 /1

    [btw, i am not a programmer, but i really like google and copy/paste...]

    cheers \ joris

    #Name: Powder Printing

    #Info: Switch off fan power during travel moves

    #Help: PowderPrinting

    #Depend: GCode

    #Type: postprocess

    #Param: fanpowermin(int:) Fan Power Min(0-255)

    #Param: fanpowermax(int:) Fan Power Max(0-255)

    ## Written by Tom Kerckhaert, based on TweakAtZ by Steven Morlock

    ## Special Thanks to Joris van Tubergen

    ## This script is licensed under the Creative Commons - Attribution - Share Alike (CC BY-SA) terms

    # Uses - Switch off fan power during travel moves

    # TODO:

    # Get rid of the unnecessary fan on / off between two G moves

    # Fan power variables do not work yet

    import re

    def getValue(line, key, default = None):

    if not key in line or (';' in line and line.find(key) > line.find(';')):

    return default

    subPart = line[line.find(key) + 1:]

    m = re.search('^[0-9]+\.?[0-9]*', subPart)

    if m == None:

    return default

    try:

    return float(m.group(0))

    except:

    return default

    with open(filename, "r") as f:

    lines = f.readlines()

    with open(filename, "w") as f:

    for line in lines:

    if getValue(line, 'G', None) == 0:

    f.write("; Powder Plugin\n")

    f.write("M106 S0\n")

    f.write(line)

    f.write("M106 S255\n")

    f.write("; Plugin: End\n")

    f.write(line)

    if getValue(line, 'G', None) == 1:

    x = getValue(line, 'X', dx)

    y = getValue(line, 'Y', dy)

    z = getValue(line, 'Z', dz)

    e = getValue(line, 'E', e)

    f = getValue(line, 'F', f)

    line = 'G1 '

    if dx != x:

    line += 'X%f ' % x

    if dy != y:

    line += 'Y%f ' % y

    if dz != z:

    line += 'Z%f ' % z

    if df != f:

    line += 'F%f ' % f

    line += '\n'

     

    # if comment is the extruder movements before and after the print, remove that line

    g.write(line)

  • Link to post
    Share on other sites

    Posted · Easiest way to turn on/off my laser for G0 moves then turn it back on for G1 draws using Cura???

    Yes, what Joris said. Write a plugin. It will be awesome. And please share it! Note also that the newest versions of Cura (15.06.* and newer) have a totally different way of doing plugins and I don't know if anyone knows how to do that yet so I would go for the older version e.g. 15.04 and I'm sure all the work you did for the plugin will still be useful - I suspect converting plugins from 15.04 to 15.06 will be pretty simple once someone documents the process.

  • Link to post
    Share on other sites

    • 2 weeks later...
    Posted · Easiest way to turn on/off my laser for G0 moves then turn it back on for G1 draws using Cura???

    Regular edits with search and replace has sped up the process considerably. Thank you for taking the time to send me your suggestion. I am considering writing a plug in to eliminate the editing for all future projects, but I don't have the time to go down that road right now.

  • Link to post
    Share on other sites

    Posted · Easiest way to turn on/off my laser for G0 moves then turn it back on for G1 draws using Cura???

    I wrote a post process plugin to solve this problem
     

    # Copyright (c) 2020 Belin Fieldson
    # LaserCode is released under the terms of the AGPLv3 or higher.
    
    from ..Script import Script
    
    class LaserCode(Script):
        version = "1.01"
        def __init__(self):
            super().__init__()
    
        def getSettingDataString(self):
            return """{
                "name":"Laser Code v.(""" + self.version + """)",
                "key":"LaserCode",
                "metadata": {},
                "version": 2,
                "settings":
                {
                    "_activation":
                    {
                        "label": "Laser Activate",
                        "description": "The code to use to activate the laser",
                        "type": "str",
                        "default_value": "M3"
                    },
                    "_deactivation":
                    {
                        "label": "Laser Deactivate",
                        "description": "The code to use to deactivate the laser",
                        "type": "str",
                        "default_value": "M5"
                    },
                    "_prefixActivation":
                    {
                        "label": "Active GCODE",
                        "description": "The gcode that the activate code should be prefixed to",
                        "type": "str",
                        "default_value": "G1"
                    },
                    "_prefixDeactivation":
                    {
                        "label": "Inactive GCODE",
                        "description": "The gcode that the deactivate code should be prefixed to",
                        "type": "str",
                        "default_value": "G0"
                    }
                }
            }"""
    
        def execute(self, data):
            activation = self.getSettingValueByKey("_activation");
            deactivation = self.getSettingValueByKey("_deactivation");
            searchActivation = self.getSettingValueByKey("_prefixActivation");
            searchDeactivation = self.getSettingValueByKey("_prefixDeactivation");
            activated = False;
            # Declare output gcode
            for layer in data:
                index = data.index(layer)
                lines = layer.split("\n")
                newLayer = ""
                for line in lines:
                    if (searchActivation in line and not activated):
                        newLayer += activation + "\n"
                        activated = True
                    if (searchDeactivation in line and activated):
                        newLayer += deactivation + "\n"
                        activated = False
                    newLayer += line + "\n"
                data[index] = newLayer
    
            return data

     

  • Link to post
    Share on other sites

    Create an account or sign in to comment

    You need to be a member in order to leave a comment

    Create an account

    Sign up for a new account in our community. It's easy!

    Register a new account

    Sign in

    Already have an account? Sign in here.

    Sign In Now
    • Our picks

      • UltiMaker Cura 5.7 stable released
        Cura 5.7 is here and it brings a handy new workflow improvement when using Thingiverse and Cura together, as well as additional capabilities for Method series printers, and a powerful way of sharing print settings using new printer-agnostic project files! Read on to find out about all of these improvements and more. 
         
          • Like
        • 7 replies
      • S-Line Firmware 8.3.0 was released Nov. 20th on the "Latest" firmware branch.
        (Sorry, was out of office when this released)

        This update is for...
        All UltiMaker S series  
        New features
         
        Temperature status. During print preparation, the temperatures of the print cores and build plate will be shown on the display. This gives a better indication of the progress and remaining wait time. Save log files in paused state. It is now possible to save the printer's log files to USB if the currently active print job is paused. Previously, the Dump logs to USB option was only enabled if the printer was in idle state. Confirm print removal via Digital Factory. If the printer is connected to the Digital Factory, it is now possible to confirm the removal of a previous print job via the Digital Factory interface. This is useful in situations where the build plate is clear, but the operator forgot to select Confirm removal on the printer’s display. Visit this page for more information about this feature.
          • Like
        • 0 replies
    ×
    ×
    • Create New...